Has anyone been able to model the XYS IXTP08N50D2 or XYS IXTP08N100D2
I have found Psice models on similar but does anyone have one built??
Just not sure how to build a model in Ltspice, Ive found how to change a pspice to ltspice but there are no psice models for those two and just need a hand. Thank you all!!
Parameter
IXTP08N50D2
VDSS, Max, (V) 500 ID(on), Min, (A) 0.80 RDS(on), Max, (Ω) 4.600 VGS(off), Max, (V) -4.5 Ciss, Typ, (pF) 312 Crss, Typ, (pF) 11 Qg, Typ, (nC) 12.7 PD, (W) 60 RthJC, Max, (ºC/W) 2.08 Package Style TO-220
Parameter
IXTP08N100D2
VDSS, Max, (V) 1000 ID(on), Min, (A) 0.8 RDS(on), Max, (Ω) 21.00 VGS(off), Max, (V) -4.0 Ciss, Typ, (pF) 325 Crss, Typ, (pF) 6.5 Qg, Typ, (nC) 14.6 PD, (W) 60 RthJC, Max, (ºC/W) 2.08 Package Style TO-220
http://www.mouser.com/ProductDetail/Ixys/IXTP08N50D2/?qs=6UKyFUzHTlmmDo5v2SbtuQ==
I have found Psice models on similar but does anyone have one built??
Just not sure how to build a model in Ltspice, Ive found how to change a pspice to ltspice but there are no psice models for those two and just need a hand. Thank you all!!
Parameter
IXTP08N50D2
VDSS, Max, (V) 500 ID(on), Min, (A) 0.80 RDS(on), Max, (Ω) 4.600 VGS(off), Max, (V) -4.5 Ciss, Typ, (pF) 312 Crss, Typ, (pF) 11 Qg, Typ, (nC) 12.7 PD, (W) 60 RthJC, Max, (ºC/W) 2.08 Package Style TO-220
Parameter
IXTP08N100D2
VDSS, Max, (V) 1000 ID(on), Min, (A) 0.8 RDS(on), Max, (Ω) 21.00 VGS(off), Max, (V) -4.0 Ciss, Typ, (pF) 325 Crss, Typ, (pF) 6.5 Qg, Typ, (nC) 14.6 PD, (W) 60 RthJC, Max, (ºC/W) 2.08 Package Style TO-220
http://www.mouser.com/ProductDetail/Ixys/IXTP08N50D2/?qs=6UKyFUzHTlmmDo5v2SbtuQ==
I have modeled two of the IXYS FETs.
You need an LTSpice VDMOS model with sub-threshold parameters to do it properly.
A search will turn up some discussion of this in a thread started by "Keantoken"
Best wishes
David
Thanks for the reply David. Could you share the models in this forum?
I looked up Keantoken but 11 pages of results, do you remember the thread name?
I looked up Keantoken but 11 pages of results, do you remember the thread name?
Hi
I will post them after I check them more carefully, been a bit busy.
Thread is http://www.diyaudio.com/forums/software-tools/266655-better-power-mosfet-models-ltspice.html
Best wishes
David
Hello David,
I was able to find a model for the IXTP01N100D which is very close to the IXTP08N50D2 or IXTP08N100D2
I do try and build it in LTSpice but get the "Unknown SPICE device type "N" in "node 1 - drain"
Getting closer. Any luck on your end? Thanks again!
* PSpice Model Editor - Version 9.2.1
*$
.SUBCKT IXTP01N100D D G S
************************************************** *******************
*Note: *
* Althought models can be a useful tool in evaluating device *
* performance, they cannot model exact device performance *
* under all conditions, nor are they intended to replace *
* bread boarding for final verification. Therefore IXYS does *
* not assume any liability arsing from their use. IXYS reserves *
* the right to change models without prior notice. The Pspice model *
* does not constitute product data sheet. Designer should refer to *
* the data sheet to guranteed the limit and specification. *
************************************************** *******************
** model generated on Jan 14, 2013
* Node 1 -> Drain
* Node 2 -> Gate
* Node 3 -> Source
M110 D G S1 S1 MM111
L_s S S1 1n
.MODEL MM111 NMOS
+ LEVEL=3
+ L=2.0000E-6
+ W=.4
+ KP=1.0431E-6
+ RS=10.000E-3
+ RD=49.597
+ VTO=-2.2067
+ RDS=1.0000E9
+ TOX=2.0000E-6
+ CGSO=25.000E-15
+ CGDO=1.9992E-12
+ CBD=105.33E-12
+ MJ=1.0378
+ PB=1.6953
+ RG=10.000E-3
+ RB=1.0000E-3
+ GAMMA=0
+ KAPPA=0
*
L_bd S2 S 1n
D_1 S2 D BD
.MODEL BD D
+ IS=626.27E-9
+ N=2.3975
+ RS=1.0000E-3
+ CJO=106.80E-12
+ M=1.1185
+ VJ=1.6503
+ ISR=1.0588E-9
+ BV=1.0001E3
+ IBV=2.6125
+ TT=270.51E-9
.ENDS
*$
I was able to find a model for the IXTP01N100D which is very close to the IXTP08N50D2 or IXTP08N100D2
I do try and build it in LTSpice but get the "Unknown SPICE device type "N" in "node 1 - drain"
Getting closer. Any luck on your end? Thanks again!
* PSpice Model Editor - Version 9.2.1
*$
.SUBCKT IXTP01N100D D G S
************************************************** *******************
*Note: *
* Althought models can be a useful tool in evaluating device *
* performance, they cannot model exact device performance *
* under all conditions, nor are they intended to replace *
* bread boarding for final verification. Therefore IXYS does *
* not assume any liability arsing from their use. IXYS reserves *
* the right to change models without prior notice. The Pspice model *
* does not constitute product data sheet. Designer should refer to *
* the data sheet to guranteed the limit and specification. *
************************************************** *******************
** model generated on Jan 14, 2013
* Node 1 -> Drain
* Node 2 -> Gate
* Node 3 -> Source
M110 D G S1 S1 MM111
L_s S S1 1n
.MODEL MM111 NMOS
+ LEVEL=3
+ L=2.0000E-6
+ W=.4
+ KP=1.0431E-6
+ RS=10.000E-3
+ RD=49.597
+ VTO=-2.2067
+ RDS=1.0000E9
+ TOX=2.0000E-6
+ CGSO=25.000E-15
+ CGDO=1.9992E-12
+ CBD=105.33E-12
+ MJ=1.0378
+ PB=1.6953
+ RG=10.000E-3
+ RB=1.0000E-3
+ GAMMA=0
+ KAPPA=0
*
L_bd S2 S 1n
D_1 S2 D BD
.MODEL BD D
+ IS=626.27E-9
+ N=2.3975
+ RS=1.0000E-3
+ CJO=106.80E-12
+ M=1.1185
+ VJ=1.6503
+ ISR=1.0588E-9
+ BV=1.0001E3
+ IBV=2.6125
+ TT=270.51E-9
.ENDS
*$
Conversion of PSpice models is tedious, adds complication, and is practically certain to be worse than LTspice's unique VDMOS model which is specifically optimized for power VFETs.
Send an email to the address in my profile and I will send you my IXYS models.
Best wishes
David
Hi Dave.
Tried to send you a email for requesting the IXYS models you have for LT-Spice, but I think your inbox is full..
I would like to have them If you would like to share.
Thanks Michael.
Tried to send you a email for requesting the IXYS models you have for LT-Spice, but I think your inbox is full..
I would like to have them If you would like to share.
Thanks Michael.
Hi Michael
I will be happy to send you the models.
My email address is in my profile, use that, more space than the DIY inbox.
Best wishes
David
Member
Joined 2009
Paid Member
Hi Dave,
I'm sensing that these are top secret models 😀
I'd like a model for the IXTP08100D2 please.
I'm sensing that these are top secret models 😀
I'd like a model for the IXTP08100D2 please.
Hi Simon
No, not secret, in fact I don't have a model for this particular MOSFET.
But I do have models of a few other IXYS MOSFETs to act as examples, and advice and links on the best procedure to use.
The main advice is that you must use the VDMOS model.
This used to be unique to LTspice but has now been cloned by open source software.
Personally I use only LTSpice VDMOS, because it works well, especially with the latest enhancements.
I assume you mean the IXTP08N100D2.
If so then there is a complication to watch out for -
This is a depletion mode device that may be difficult to model, I haven't tried it myself.
Ian Hegglund may have done one and he is probably the most experienced with this, his latest articles are more detailed than my work.
I recommend you check his latest posts and links.
Best wishes
David
Hi Dave,
Wondering if you can send me a model of the IXTP01N100D? Your msg inbox is full so can't send you a PM.
Hi.
.model IXTY08N100D2 Vdmos vto=-2.5 kp=1 Rg=5 lambda=50m Cgs=320p Cgdmin=5.5p Cgdmax=300p Cjo=600p Rs=1 Rd=5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.15 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTP08N100D2 Vdmos vto=-2.5 kp=1 Rg=5 lambda=50m Cgs=320p Cgdmin=5.5p Cgdmax=300p Cjo=600p Rs=1 Rd=5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.15 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTY1R6N100D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTP1R6N100D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTY1R6N50D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=500 nbv=10 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=500
.model IXTP1R6N50D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=500 nbv=10 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=500
.model IXTY08N100D2 Vdmos vto=-2.5 kp=1 Rg=5 lambda=50m Cgs=320p Cgdmin=5.5p Cgdmax=300p Cjo=600p Rs=1 Rd=5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.15 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTP08N100D2 Vdmos vto=-2.5 kp=1 Rg=5 lambda=50m Cgs=320p Cgdmin=5.5p Cgdmax=300p Cjo=600p Rs=1 Rd=5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.15 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTY1R6N100D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTP1R6N100D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=1000 nbv=20 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=1000
.model IXTY1R6N50D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=500 nbv=10 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=500
.model IXTP1R6N50D2 Vdmos vto=-2.5 kp=2 Rg=2.5 lambda=50m Cgs=640p Cgdmin=11p Cgdmax=700p Cjo=2n Rs=0.2 Rd=0.5 BV=500 nbv=10 ksubthres=.2 mtriode=0.5 Theta=0.5 TT=1u mfg=Ixys Vds=500
Hi all,
The post by Bordodynov provides a model for IXYS Jfets.
I am looking for IXTH6N50D2 - To-247.
Is that the same as for IXT-Y/P-1R6N50D2, which all have a different housing?
So I can just rename it? I'm 99% sure like often 🙄
Role: for 1.2 Amp CCS for 2SK180.
regards
albert
The post by Bordodynov provides a model for IXYS Jfets.
I am looking for IXTH6N50D2 - To-247.
Is that the same as for IXT-Y/P-1R6N50D2, which all have a different housing?
So I can just rename it? I'm 99% sure like often 🙄
Role: for 1.2 Amp CCS for 2SK180.
regards
albert
No. They are different power transistors. You have to make a new model for this transistor. Compare the datasheet.
