• WARNING: Tube/Valve amplifiers use potentially LETHAL HIGH VOLTAGES.
    Building, troubleshooting and testing of these amplifiers should only be
    performed by someone who is thoroughly familiar with
    the safety precautions around high voltages.

Problem with KT88 Williamson LTSpice simulation

Status
This old topic is closed. If you want to reopen this topic, contact a moderator using the "Report Post" button.
Jump to Latest
D

dch53

Member
Joined 2015
Hi,

Can someone please tell me why I'm getting 100+KV on the grids of the KT88s in this simulation? The valves are dissipating 100+KW!

Thanks.

LTSpice schematic.jpg

\\\M:\Entertainment\HiFi\Valve stuff\Williamson Amplifier Material\LTspice model\LTSpice Schematic.jpg
 

Attachments

  • kt88 williamson.zip
    4.8 KB · Views: 51
D

dch53

Member
Joined 2015
So now I have the dc operating points. When I try to run 10ms of 4Khz sine wave I get:

WARNING: Node U3:A is floating.
WARNING: Node U3:K is floating.
WARNING: Node U3:G2 is floating.
WARNING: Node U3:G1 is floating.
WARNING: Node U4:A is floating.
WARNING: Node U4:K is floating.
WARNING: Node U4:G2 is floating.
WARNING: Node U4:G1 is floating.

WARNING: Less than two connections to node N008. This node is used by R16.
WARNING: Less than two connections to node N030. This node is used by R19.
WARNING: Less than two connections to node N031. This node is used by L4.
WARNING: Less than two connections to node N012. This node is used by L5.
WARNING: Less than two connections to node N011. This node is used by R20.
WARNING: Less than two connections to node N027. This node is used by R21.
WARNING: Less than two connections to node N033. This node is used by R22.
WARNING: Less than two connections to node N004. This node is used by L1.
Direct Newton iteration for .op point succeeded.
Ignoring empty pin current: Ix(u3:anode)
Ignoring empty pin current: Ix(u3:screen)
Ignoring empty pin current: Ix(u3:grid)
Ignoring empty pin current: Ix(u3:cathode)
Ignoring empty pin current: Ix(u4:anode)
Ignoring empty pin current: Ix(u4:screen)
Ignoring empty pin current: Ix(u4:grid)
Ignoring empty pin current: Ix(u4:cathode)
Ignoring empty pin current: Ix(u3:anode)
Ignoring empty pin current: Ix(u3:screen)
Ignoring empty pin current: Ix(u3:grid)
Ignoring empty pin current: Ix(u3:cathode)
Ignoring empty pin current: Ix(u4:anode)
Ignoring empty pin current: Ix(u4:screen)
Ignoring empty pin current: Ix(u4:grid)
Ignoring empty pin current: Ix(u4:cathode)
Singular matrix: Check node u3:g1
Iteration No. 2
Fatal Error: Singular matrix: check node u3:g1
Iteration No. 2

This circuit has floating nodes.

Is there still a problem with the KT88 model?
 
K

Koonw

Disabled Account
Joined 2013
dch53 said:
So now I have the dc operating points. When I try to run 10ms of 4Khz sine wave I get:

WARNING: Node U3:A is floating.
WARNING: Node U3:K is floating.
WARNING: Node U3:G2 is floating.
WARNING: Node U3:G1 is floating.
WARNING: Node U4:A is floating.
WARNING: Node U4:K is floating.
WARNING: Node U4:G2 is floating.
WARNING: Node U4:G1 is floating.

WARNING: Less than two connections to node N008. This node is used by R16.
WARNING: Less than two connections to node N030. This node is used by R19.
WARNING: Less than two connections to node N031. This node is used by L4.
WARNING: Less than two connections to node N012. This node is used by L5.
WARNING: Less than two connections to node N011. This node is used by R20.
WARNING: Less than two connections to node N027. This node is used by R21.
WARNING: Less than two connections to node N033. This node is used by R22.
WARNING: Less than two connections to node N004. This node is used by L1.
Direct Newton iteration for .op point succeeded.
Ignoring empty pin current: Ix(u3:anode)
Ignoring empty pin current: Ix(u3:screen)
Ignoring empty pin current: Ix(u3:grid)
Ignoring empty pin current: Ix(u3:cathode)
Ignoring empty pin current: Ix(u4:anode)
Ignoring empty pin current: Ix(u4:screen)
Ignoring empty pin current: Ix(u4:grid)
Ignoring empty pin current: Ix(u4:cathode)
Ignoring empty pin current: Ix(u3:anode)
Ignoring empty pin current: Ix(u3:screen)
Ignoring empty pin current: Ix(u3:grid)
Ignoring empty pin current: Ix(u3:cathode)
Ignoring empty pin current: Ix(u4:anode)
Ignoring empty pin current: Ix(u4:screen)
Ignoring empty pin current: Ix(u4:grid)
Ignoring empty pin current: Ix(u4:cathode)
Singular matrix: Check node u3:g1
Iteration No. 2
Fatal Error: Singular matrix: check node u3:g1
Iteration No. 2

This circuit has floating nodes.

Is there still a problem with the KT88 model?
Click to expand...

I forget to tell you: replace all "^" with "**" in KT88.inc, if you use LTSpsice
 
D

dch53

Member
Joined 2015
Just getting noise on the output

I now have the KT88 grids at -60V with a 120V peak-to-peak 4khz signal (swinging between 0V and -120V).

But there's only noise on the output.

Updated files attached.

Any suggestions please?

LTSpice schematic.jpg
 

Attachments

  • kt88 williamson.zip
    4.9 KB · Views: 30
K

Koonw

Disabled Account
Joined 2013
dch53 said:
I now have the KT88 grids at -60V with a 120V peak-to-peak 4khz signal (swinging between 0V and -120V).

But there's only noise on the output.

Updated files attached.

Any suggestions please?

View attachment 536939
Click to expand...

I don't all the asy so I use mine, it works.
 

Attachments

  • 6GU7 Williamson with KT88 dc op.asc
    10 KB · Views: 53
  • snapshot-1.png
    snapshot-1.png
    255.4 KB · Views: 98
Last edited:
D

dch53

Member
Joined 2015
Thanks koonw. I'm not getting the same result as you though.

I downloaded your file and adjusted the potentiometer and kt88 includes.

When I run the sim I get a 4khz output with an amplitude of only 50uV centred on 55uV instead of the 30V centered on 0V that you have.

The only difference I can suggest is the kt88 model. The one I'm using is attached.
 
K

Koonw

Disabled Account
Joined 2013
dch53 said:
Thanks koonw. I'm not getting the same result as you though.

I downloaded your file and adjusted the potentiometer and kt88 includes.

When I run the sim I get a 4khz output with an amplitude of only 50uV centred on 55uV instead of the 30V centered on 0V that you have.

The only difference I can suggest is the kt88 model. The one I'm using is attached.
Click to expand...

Use a notepad, replace all "^" with "**" as follow, NO need to change pin tetrode asy (unless you have changed it, check) as mentioned earlier, the problem is in the model file as it is not a native LTSpice file, so apply to other model as well.

*
* Generic pentode model: KT88
* Copyright 2003--2008 by Ayumi Nakabayashi, All rights reserved.
* Version 3.10, Generated on Sat Mar 8 22:42:55 2008
* Plate
* | Screen Grid
* | | Control Grid
* | | | Cathode
* | | | |
.SUBCKT KT88 A G2 G1 K
BGG GG 0 V=V(G1,K)+0.99999999
BM1 M1 0 V=(0.097534908*(URAMP(V(G2,K))+1e-10))**-1.4398564
BM2 M2 0 V=(0.51022901*(URAMP(V(GG)+URAMP(V(G2,K))/5.0214944)))**2.9398564
BP P 0 V=0.0031096914*(URAMP(V(GG)+URAMP(V(G2,K))/9.8416483))**1.5
BIK IK 0 V=U(V(GG))*V(P)+(1-U(V(GG)))*0.0029317575*V(M1)*V(M2)
BIG IG 0 V=0.0015548457*URAMP(V(G1,K))**1.5*(URAMP(V(G1,K))/(URAMP(V(A,K))+URAMP(V(G1,K)))*1.2+0.4)
BIK2 IK2 0 V=V(IK,IG)*(1-0.4*(EXP(-URAMP(V(A,K))/URAMP(V(G2,K))*15)-EXP(-15)))
BIG2T IG2T 0 V=V(IK2)*(0.88165022*(1-URAMP(V(A,K))/(URAMP(V(A,K))+10))**1.5+0.11834978)
BIK3 IK3 0 V=V(IK2)*(URAMP(V(A,K))+1850)/(URAMP(V(G2,K))+1850)
BIK4 IK4 0 V=V(IK3)-URAMP(V(IK3)-(0.0020406477*(URAMP(V(A,K))+URAMP(URAMP(V(G2,K))-URAMP(V(A,K))))**1.5))
BIP IP 0 V=URAMP(V(IK4,IG2T)-URAMP(V(IK4,IG2T)-(0.0020406477*URAMP(V(A,K))**1.5)))
BIAK A K I=V(IP)+1e-10*V(A,K)
BIG2 G2 K I=URAMP(V(IK4,IP))
BIGK G1 K I=V(IG)
* CAPS
CGA G1 A 1.2p
CGK G1 K 9p
C12 G1 G2 6p
CAK A K 10.9p
.ENDS
 
Status
This old topic is closed. If you want to reopen this topic, contact a moderator using the "Report Post" button.
Top Bottom